A revolved bushing
A flanged bushing turned from its half section. The section is drawn
on XZ, its x running out from the axis and its y up world Z, and
design.revolve turns it a full turn about the sketch's
y-axis, which is what it does when given no axis. A chamfer then breaks
the sleeve's top outer edge, picked by a point on the circle and the way
the circle runs there.
The test suite runs this block from an empty document, and its asserts check what it made.
local ri, rs, rf = 4, 7, 12 -- bore, sleeve and flange radii
local hf, h = 3, 15 -- flange thickness, overall height
local section = pc.sketch.new{plane = "XZ", name = "Section"}
pc.sketch.polyline{sketch = section, closed = true, points = {
{ri, 0}, {rf, 0}, {rf, hf}, {rs, hf}, {rs, h}, {ri, h},
}}
local turn = pc.design.revolve{sketch = section}
local body = pc.doc.feature{id = turn}.body
-- The top outer edge is a circle of radius rs at height h: at (0, rs, h)
-- it runs along X.
pc.design.chamfer{body = body, size = 1,
edges = {Edges = {{point = {0, rs, h}, direction = {1, 0, 0}}}}}
assert(#pc.doc.rebuild() == 0, "every feature builds")
-- The turned section, less the chamfer's triangle turned at its centroid.
local turned = math.pi * ((rf * rf - ri * ri) * hf + (rs * rs - ri * ri) * (h - hf))
local chamfer = 0.5 * 2 * math.pi * (rs - 1 / 3)
local volume = pc.doc.measure{body = body}.volume
assert(math.abs(volume - (turned - chamfer)) < 0.01, volume)
local radii, cones = {}, 0
for _, face in ipairs(pc.doc.faces{body = body}) do
if face.kind == "cylinder" then radii[#radii + 1] = face.radius end
if face.kind == "cone" then cones = cones + 1 end
end
table.sort(radii)
assert(#radii == 3 and radii[1] == ri and radii[2] == rs and radii[3] == rf,
"the bore, the sleeve and the flange")
assert(cones == 1, "the chamfer is one cone")